PCBA quote documentation - what an EMS provider needs for a binding price

Published:

Two quotes for assembling the same board can differ by more than the two suppliers' costs would justify. Part of the reason is not the rates, it is the documentation. An EMS provider does not quote the board, it quotes what it was told about the board. Whatever is missing from the bill of materials, the production files or the quality requirements, the supplier has to assume. One company adds a risk margin to the price, another assumes the cheapest option and comes back with a correction after the order is placed. The two quotes then answer different questions.

This article describes the documentation that lets a contract manufacturer quote PCB assembly without guessing. For each item it shows which assumption its absence forces.

Every gap in the documentation becomes an assumption, and every assumption becomes a price

A PCBA quote is made of several parts that react to missing information in different ways. Components and bare boards are purchases, so their price depends on knowing exactly what to buy. Production setup covers the paste stencil, machine programs and any test fixtures, so it depends on complete geometric data. Assembly and inspection depend on the technology, the product class and the acceptance requirements.

A gap in the first group ends in a conditional quote, or in a quote for a more expensive component than necessary. A gap in the second group moves work to after the order, when the process engineer starts asking questions and the lead time is already running. A gap in the third group is the most dangerous, because it is invisible in the quote. It surfaces at acceptance, when it turns out that customer and supplier understood "a good board" differently.

A BOM is quoted by manufacturer part number, not by value

A BOM line reading "resistor 10 kΩ 0603" does not let anyone buy a specific part. It says nothing about tolerance, temperature coefficient, power rating, or whether the assembly needs a part with a particular qualification. The supplier can pick the cheapest equivalent or ask. In the first case the risk moves to the customer, in the second the quote takes longer.

A quote-ready BOM has, for every line:

  • The manufacturer and its part number (MPN). A distributor part number is not enough, because the same part is often sold under different numbers.
  • Reference designators that match the board design. R1, C12 and U3 in the BOM must match the same designators in the pick-and-place data. A mismatch stops machine programming.
  • The quantity per board, consistent with the number of designators on that line.
  • Do-not-place (DNP) items marked explicitly, not silently removed from the list. To a process engineer, a pad without a part and no BOM line looks exactly like a mistake.
  • Approved alternates, or a clear statement that there are none.

The last point carries more weight than it seems. The IPC-2581C format (November 2020), which describes board fabrication and assembly data in a single XML file, has separate sections for the BOM and for the approved vendor list (AVL). Alternates are a separate piece of information there, not a note in a comment field. An alternate can also be a process change, not just a purchasing one. A part with the same function but a different lead geometry may need a stencil correction, as we describe in the article on SMT assembly defects.

You also need to decide who buys the components. If the EMS provider sources everything, the quote covers availability, minimum order quantities and price risk. If the customer supplies the parts (consignment), the quote has to state in what form they are accepted. Parts on tape and reel and the same parts loose are two different situations for an SMT line.

Gerber files describe the board, but not how to assemble it

An assembly quote needs the copper, solder mask, solder paste and legend layers, plus the drill files and board outline. The paste layer is the basis of the stencil design. If it is missing, the supplier will generate it from the pads, which does not always match the designer's intent.

The Gerber format specification maintained by Ucamco (current revision 2026.05) lets you attach attributes to the files. They can describe the function of each layer and even carry the netlist from the CAD design. The specification justifies this with data transfer security: comparing the connectivity calculated from the image with the CAD netlist catches an error before the board goes into production. Since revision 2020.09 the format also includes the X3 variant with component data: position, rotation, manufacturer, part number and package name.

If the EMS provider is to buy the bare boards, the quote also needs the fabrication data: material, thickness, stack-up, surface finish and copper weight. It also needs the specification and class the board is to be accepted against. For rigid boards, the qualification requirements are set out in IPC-6012F from September 2023.

A pick-and-place file without a zero-orientation declaration is ambiguous

The pick-and-place file, also called the XY or centroid file, gives the coordinates, rotation angle and board side for every component. Coordinates and side rarely cause trouble. Rotation does, because the number 0 means nothing until you know what it was measured against.

IEC 61188-7:2017 describes two zero-orientation conventions for CAD libraries. At level A, pin 1 of a multi-lead part sits at the top or top-left. At level B it sits at the left or bottom-left. The standard names level B as preferred for new libraries. At the same time, the Gerber specification defines component rotation zero in X3 data as in IPC-7351B. Two currently maintained documents therefore refer to different reference points.

IEC 61188-7:2017 resolves this on the data side. Clause 4.1 requires that, when information is transferred to an assembler, the orientation is defined without ambiguity or corrected. Clause 4.5 calls stating the level used, A or B, a mandatory requirement in the file header. If the file does not carry that information, the process engineer has to establish orientation by hand from the assembly drawing and polarity markings.

That is why the XY file should come with:

  • the orientation convention used in the CAD library,
  • units and the coordinate origin, ideally also marked on the drawing,
  • how bottom-side parts are recorded, because mirroring changes how the angle is read,
  • an assembly drawing showing pin 1 and component polarity.

The assembly drawing is a safeguard no file format replaces. It lets the first assembled board be checked without guessing which orientation is right.

The product class and acceptance criteria must be stated before the price is

IPC standards divide products into three classes: Class 1 is general electronic products, Class 2 dedicated service electronic products, and Class 3 high performance or harsh environment electronic products. The class in the request sets the acceptance criteria under IPC-A-610J (March 2024) and how tightly the process has to be controlled. A request without a class forces the supplier to make an assumption that may not match what the customer expects.

IPC-A-610J also contains a caveat worth knowing before ordering. Clause 1.2 says the document applies when the assembly complies with other existing IPC requirements, naming IPC-7351, IPC-222X, IPC-601X and IPC-A-600. If it does not, the standard is explicit: "the acceptance criteria shall be defined between the User and Supplier". A requirement such as "assembly to IPC-A-610" therefore does not settle the matter when the board design departs from those standards. The same standard also contains no criteria for X-ray inspection, which also has to be agreed separately.

Traceability works the same way. IPC-1782B (September 2023) describes four levels of traceability for materials and processes, from basic to comprehensive. It includes tables of recommended levels for Classes 1, 2 and 3, and for Class 3 with market addenda. The traceability level determines what data the supplier has to collect for each board. If the product requires it, the request should state it.

Test, programming and secondary processes are separate quote items

Assembly ends with soldered components. Everything after that needs its own information in the request:

  • Electrical or functional test. Agree who supplies the test fixture, the procedure and the pass criterion. A tester designed by the EMS provider is a separate project with its own setup cost.
  • Device programming. The supplier needs the firmware file, the stage at which to program and the verification method.
  • Cleaning and conformal coating. For PCBA coating the price depends on which areas must stay uncoated. Without a drawing of the keep-out areas, the supplier cannot judge the masking effort.
  • Through-hole and final assembly. The number of THT parts and how they are soldered change the quote independently of the SMT part. Box build, cabling and packing also need to be described.

Volume in a request is at least three numbers, not one

Setup costs, meaning the stencil, machine programs and fixtures, are spread over the number of boards built. A single "quantity" in the request is therefore not enough. The supplier needs the first batch size, the expected annual volume and the size of follow-on batches.

These three numbers also affect purchasing. Minimum order quantities and full-reel packaging mean that on a small batch some purchased parts stay in stock. The quote should say clearly who pays for them and what happens to them. For a prototype the same questions weigh differently than for a production run, so state which case the request is about.

What to send so the quote is not an estimate

A complete PCBA quote package contains:

  1. A BOM with manufacturer, MPN, reference designators, quantity, DNP items and approved alternates.
  2. Gerber files for all layers, including paste, with drill files and outline, or a single IPC-2581C file.
  3. A pick-and-place file with the orientation convention, units, origin and bottom-side convention.
  4. An assembly drawing showing pin 1 and polarity.
  5. Bare board fabrication data, if the EMS provider is to buy the boards.
  6. The product class, acceptance criteria and required traceability level.
  7. Requirements for test, programming, cleaning, coating and final assembly.
  8. First batch size, annual volume and follow-on batch size.

The request a quote form at EAE Elektronik accepts up to five files of up to 10 MB each, in ZIP, CSV, XLS, XLSX, PNG and JPG formats. Gerber files, pick-and-place data and PDF drawings are best packed into a single ZIP archive, with the BOM attached as a spreadsheet. We source components and bare boards, and we build testers and programmers for products that need them. The full scope of our EMS services is described on the service page.

Let's talk!

Take the first step! Write or call and let's talk about your project.
We will present you our offer and choose the optimal solution.

contact us
eae elektronik montaż smt